Scallop Height: Picking Ball Nose Size and Stepover
Scallop height is the ridge a ball nose end mill leaves between passes. How stepover and ball size set it, with worked numbers for inch and metric tools.
Don Grandt of In The Loupe TV, Harvey Performance's channel, opens his ball nose episode with the question every sculpted part raises: what is scallop height, and how do you change it? If your part has a curved face, that ridge pattern is what the finishing pass is paid to shrink.
What Is Scallop Height on a Ball Nose Finish?
Scallop height is the height of the small ridge left between two neighboring passes of a ball nose end mill. The stepover between passes and the radius of the ball set it.
In Ball Nose End Mills & Scallop Height, Don draws it as a cusp at the top and a root at the bottom, and says the distance between them is what controls your finish. He shows it with a 1/2 in ball nose. Tighten the stepover and the cusp shrinks. Then he keeps the stepover, moves up to a 3/4 in ball, and the finish improves again. The bigger ball can also cover the surface in fewer passes, as long as it fits the geometry.
Putting Numbers on the Ridge
The geometry is simple. Machining Doctor's ball nose surface finish page gives it as h = r minus the square root of (r squared minus p squared over 4), where r is the ball radius and p is the stepover.
Run Don's two tools through it on a flat face. A 1/2 in ball at 0.020 in stepover leaves about 0.0002 in. Halve the stepover to 0.010 in and it drops to about 0.00005 in, a quarter of the height for twice the passes. Keep 0.020 in and switch to a 3/4 in ball and you get about 0.00013 in.
In metric, a 10 mm ball at 0.5 mm stepover leaves about 0.006 mm. Open it to 1 mm and the scallop grows to about 0.025 mm. Machining Doctor suggests a stepover around 30% of the ball radius as the sweet spot, since going tighter adds time for little visible gain.
Those are ideal numbers. Runout, deflection and surface slope all change what you measure. It's also a peak-to-valley figure, not an Ra average, so read Ra vs Rz before you translate one into the other.
What to Put on the Drawing
Call the finish you need, not a stepover. If a face only has to look clean, a looser finish saves real machine time. Our post on finish straight off a 3-axis mill covers the baseline, and witness marks where passes overlap covers a related defect.
On Your Part
Our CNC page lists 3-, 4- and 5-axis milling, and the quote prices machining time from your geometry, so a fine finish on a big sculpted face shows up as minutes. If a surface needs a measured roughness report, ask us when you quote.
Need a part made?
Upload your file for an instant price.